Hole Series & Fasteners for Fusion 360 — User Guide

Platform: Windows. macOS is not included in this release.

Hole Series & Fasteners creates and edits aligned holes across parts from the assembled context in Autodesk Fusion. From a Hybrid parent design, select local components or supported directly linked source files. The linked workflow applies features to the part files, saves their changes and updates the parent references, so you do not have to recreate the same connection separately in each file. Matching metric and UNC/UNF hardware, local connection recipes, shared Cut/Intersect operations and a hardware parts list complete the workflow.

New in 1.0.1

• Mount to the holes a part already has. Pick the flat face of a motor, bearing block or rail as the hole centers: every round hole on it becomes a center, the size is read from its thread or diameter, the part keeps its holes and the screws go into its threads or through its holes. See Mount to existing holes.
• Adjustment slots through one part or the whole stack, with a washer on the slot side. See Adjustment slots.
• More hardware: nylon-insert lock nuts, hex flange bolts and nuts, fine metric pitches, inch Button, 82° Flat and Hex heads, and ISO 8734 dowel pins in Dowel H7 holes. See Fastener Stack.
• Order-ready Hardware BOM: each row names the part to order, such as ISO 4762 M6 × 20, with a search link; a company catalog can add the grade. See Export Hardware BOM.
• Hole chart per part: every hole in each part with its position in the part's own coordinates, drill, thread, tap drill, recess and depth, as CSV or a printable page. See Hole chart per part.

Replace hole centers in Edit Assembly Feature lets you revise the complete position selection while retaining the managed connection. Linked edits preserve the existing source-file set and the original references of retained axes. Saved and replacement counts and coordinates help review the selection before OK.

Linked Hole Series creation and rebuilds now check planned hardware seating, screw length and engagement before changing source files. Size and head-treatment edits use the same recess dimensions as Create, while preserving explicit clearance and nut-pocket settings when only the head treatment changes.

Update All keeps unchanged managed features' revision records consistent when later managed operations update the same linked source body, avoiding false Changed audit results after reopening. A completed update with warnings reports success and keeps the warnings visible for review.

Batch change can filter connections by their current thread size, select the matching records together, and clear the selection. Connection labels show the size, treatments and local or linked-file scope so you can review a larger assembly before changing it. The Connection Library and Batch Change command and the Export Hardware BOM command now have distinct icons so they are easier to find. Local edits and updates reduce repeated rebuilding of later features in the timeline.

Quick start

1. Open a Hybrid Fusion Design with Capture Design History enabled.
2. In the Design workspace, open the Solid tab and find the Hole Series panel beside Assemble. Hole Series, Fastener Stack and Assembly Cut appear directly on the ribbon. Open the panel dropdown for Edit Assembly Feature, Update All, Connection Library and Batch Change, Audit Assembly, Export Hardware BOM, and About Hole Series and Fasteners.
3. To reopen this guide from Fusion, choose About Hole Series and Fasteners, then Open Help.
4. Create a Hole Series, optionally create a linked Fastener Stack, then use Fusion's Get Latest or update-reference command when linked source definitions changed before running Update All.
5. Run Audit before releasing a drawing or manufacturing package.

Audit conservatively marks a changed source revision as Changed. Fusion can also change that revision after Compute All or display changes; the notice does not prove that the shape changed. Run Update All to recheck the stored inputs and rebuild the managed objects. During its own source updates, Hole Series & Fasteners keeps unchanged managed features' revision records consistent with subsequent managed operations on the same part. This does not dismiss actual geometry changes or unresolved references. External file changes still require Fusion's Get Latest before Update All.

Create and edit holes across linked Fusion files

Creation, Edit, Update and batch changes require a Hybrid parent. A direct command in a Part or Assembly design stops before changing geometry. Open or create a Hybrid parent and place your parts there; a directly linked Part source can participate in a supported Hole Series or Assembly Cut job. No design intent is converted automatically. Audit and Hardware BOM export are read-only.

1. Use a saved Hybrid parent with Capture Design History. Finish open commands and use Fusion's Get Latest or update-reference command for every affected reference. Save the parent so it is clean and at the current cloud version.
2. Run Hole Series in the parent. Select the centers, direction and target bodies, then choose supported thread size and head/tail treatments.
3. Review the selected targets and apply the command. The linked job checks the supported file context before writing sources, then processes each unique affected source sequentially.
4. After the parent returns with updated references, use Edit Assembly Feature to change supported settings on that managed connection. The saved linked source-file set remains fixed; adding or removing a source requires Delete and Create.
5. If geometry or component placement changes, make external references current first, then use Update All and review Audit Assembly. Update All does not fetch external updates automatically.

Linked parts inside linked subassemblies

A target body can sit in a part that is linked inside a linked subassembly, up to 5 link levels below the parent. Select it in the parent as usual. The confirmation lists each linked subassembly with the nested files under it. The job then saves the files bottom-up: first the deepest file with the new feature, then each linked subassembly with its link updated to that new version, and last the parent.

• A nested file must be reached through one linked subassembly only. If the same part is also linked directly in the parent or inside another subassembly, the job is refused, because that copy would stay on the old version. Copies inside the same subassembly follow All instances.
• Close every linked subassembly that will be saved before you run the command; Hole Series & Fasteners must save a new version of it. The part that holds the target may stay open when it has no unsaved changes. Close any other open design that also uses the nested part.
• Every linked subassembly that is saved must be a Hybrid design. Read-only, still processing, configured or derived subassemblies and nested parts are refused.
• Every link on the way must use the latest version. If a subassembly uses an older version of its part, open the subassembly, update its references and save it, then update the parent and try again.
• Edit keeps the nested file set fixed. Moving targets into or out of a nested part requires Delete and Create.
• A Fastener Stack created inside the linked subassembly that uses the nested part is not refreshed by a job started in the parent. Audit in that subassembly reports it as changed; open the subassembly and run Update All there.

Source saves are real Autodesk cloud versions. A later failure cannot roll them all back as one transaction: the job retains committed checkpoints and reports the partial result. Review that report before retrying; see Edit, Update All, and Audit and Current limitations.

Hole Series

1. Select one or more centers: circular edges, cylindrical faces, vertices, sketch points, construction points, or the flat face of a part that already has round holes (see Mount to existing holes).
2. For point centers, optionally select a planar face, linear edge, or construction axis to define direction.
3. Select solid target bodies, or use automatic target detection.
4. Choose Thread size (metric or UNC/UNF) and clearance fit, then the supported head and tail treatments.

Head treatments are Simple, Counterbore, and Countersink. Tail treatments are Clearance, Tapped, and Nut Pocket. The add-in measures actual axis/body intersections, so oblique parts use material thickness at the hole rather than a bounding-box estimate. A linked counterbore seats a socket-head screw at the bottom of its recess and suppresses the head-side washer.

Tapped holes use Fusion's native thread data and the selected metric or Unified thread designation. Fine metric pitches (M8x1 to M24x2) are listed after their coarse size and tap with that exact pitch. Enable modeled hole threads only when the detailed geometry is needed. Metric countersinks are 90°; inch countersinks are 82° at the flat head's theoretical sharp diameter, so an ASME B18.3 flat head sits flush.

Dowel H7 in Clearance fit makes reamed holes at the pin's nominal diameter for ISO 8734 dowel pins (2 to 20 mm). It takes a Simple head side and a Clearance tail, and Add fasteners places a pin across the joint instead of a screw.

Mount to existing holes

To bolt a bought part (a motor flange, a bearing block, a linear rail) to your parts, pick the face of that part which touches them as the hole centers. Every round hole on the face becomes a center. The dialog reads the size from a Fusion thread on the hole, or else from its diameter, sets Thread size to it and says how it read it.

• Keep mounting part (on by default) leaves that part as it is. Only the other parts are drilled.
• A threaded part (a motor with M5 threads) gets the screws from the other side: the other parts receive clearance holes, the tail stays Clearance and the screws end in the part's own threads, no deeper than the threads are.
• A part with clearance holes (a bearing block) takes the screw heads: the head-side feature is Simple, you choose the tail for the other parts (Tapped, or Clearance with a nut), and a head sits on the floor of the part's counterbore or in its countersink without a washer.

Holes in that part starts with how the holes were read, Threads or Clearance holes. Correct it when the reading is wrong, for example a rail whose 6 mm holes for M5 screws read as M6 threads, and choose the size. The kept part stays out of the series on Edit and Update All as well. When no size matches the hole diameter, choose the size yourself.

Adjustment slots

Set Slot travel above zero to make slots instead of round holes: the travel is how far the screw can move, centre to centre, and the slot is as wide as the hole diameter. Slot in chooses the first part (under the screw head), the last part or all parts; the others keep round holes. The slot runs along the X axis unless you pick a straight edge, sketch line or construction axis as Slot direction. With Add fasteners, a washer goes on each slotted side.

A slotted part takes a Simple head side and a Clearance tail, so a part that is tapped or holds a nut pocket keeps a round hole. Edit can change the travel and which parts are slotted. Slots are made in local components; a linked-file series cannot have slots yet.

A target the hole enters on a curved or steeply tilted face, such as the wall of a round tube or bar, has no flat face square to the hole axis for Fusion's Hole feature. Hole Series & Fasteners drills it with a plain cut of the hole diameter along the axis, through that whole target. Such a target takes a Simple head and a Clearance tail only: a Counterbore or Countersink head, a Tapped or Nut Pocket tail, or a tail insert there is refused before any file is changed. The same applies when the only flat face is on the far side, such as a half-round rail drilled through its round side: a Counterbore or Countersink head or an insert needs a flat face where the hole enters the target, and a Nut Pocket needs one where the hole leaves the last target.

Targets may belong to the current assembly or to directly linked Fusion source files. For linked targets, save the clean parent and make every affected reference current first. One command then preflights every affected CAD file, edits and saves each unique source once, updates the exact parent references and, on success, saves one final parent version. You do not have to open each part and recreate its hole manually.

Fastener Stack

A Fastener Stack can be linked to a Hole Series so its hardware follows that connection. This relationship is separate from a linked Fusion file, which is an external source document. Local recipes and batch changes use the former relationship; their hardware workflow does not extend to distributed source-file connections.

Link to a Hole Series, or select centers and grip bodies independently. Hole Series & Fasteners calculates grip, thread engagement, washers, nut height, and protruding threads before choosing the next configured preferred length. Joints can be a through bolt or tapped screw.

Nut type chooses the nut of a through bolt: Hex (ISO 4032; fine pitch ISO 8673; inch ASME B18.2.2), Nylon lock (thin ISO 10511; fine pitch ISO 10512; inch ASME B18.16.6) or Flange (ISO 4161, M5 to M20). A flange head or a flange nut bears on its own flange, so it takes no washer. A nut pocket holds a hex nut. A size without sourced data for a head or nut style is refused with the styles it does have.

A Dowel pin needs no washer, nut or thread. Its length is the longest ISO 8734 length that fits the joint, at most twice the diameter in each part, and it is centred on the joint between the first two parts. A joint thinner than the shortest pin is refused with that length.

The three Follow Hole Series options independently synchronize size, head seat, and termination. Nut Pocket automatically places a captive nut in the pocket without adding an external nut or exit-side washer. Turning a Follow option off preserves that Fastener Stack's own selection on later Update All operations.

Length checks run before creation or replacement. A short fastener or a preferred screw length that exceeds the measured depth stops with the required minimum and available maximum. Adjust Requested thread engagement, or choose an available Manual length with Preferred lengths only off. A corrupt existing company geometry catalog stops the operation with its path and repair guidance, leaving the previous stack unchanged.

Export Hardware BOM

Open the Hole Series panel dropdown and choose Export Hardware BOM, keep Report on Hardware BOM, select CSV (spreadsheet), the default, or HTML (printable A4), then choose a local filename with the matching extension. The export groups managed hardware by role, size, length, reference standard and recorded geometry dimensions. Head/tail washers share a washer row. Repeated component instances multiply quantities; hidden hardware counts, suppressed occurrences do not. Missing managed bodies block export so an incomplete assembly cannot silently produce a short parts list.

Each row names the part to order: the standard, thread and length for a metric screw (ISO 4762 M6 × 20, ISO 8676 M10 × 1.25 × 20), the nominal size for a washer (ISO 7089 6) and the inch size, length and head for inch hardware (1/4-20 UNC × 5/8 in flat head socket screw, ASME B18.3). A link searches the web for that designation. The designation never includes a grade, material or finish the model does not know; your company catalog can add one per kind of hardware, and point the links at your supplier's search (see Local data).

CSV keeps the established 14 columns in their order and adds designation and search_url after them. The self-contained HTML report opens offline and presents numbered items, quantities, designations, readable dimensions in millimetres, supplier and mapping status, project name, export date, inventory scope and geometry basis. Use your browser's Print command with A4 portrait paper to print or save a PDF. Exact recorded values and contributing stack IDs remain in the HTML file. The report does not invent material, grade, price or supplier information.

Both formats recheck the current inventory after the Save dialog and replace only the chosen file after a complete write. Canceling creates no file, and a failed write preserves the previous output.

Old stacks without recorded dimensions remain identifiable by stack ID and generate a warning; rebuild them to consolidate matching parts across stacks. The export covers locally indexed Hole Series & Fasteners stacks, not unopened linked documents or hardware from other tools. Supplier fields come from the optional parts section of your company catalog. Hole Series & Fasteners IDs are not vendor SKUs; verify every supplier mapping and specification. See Hardware BOM and company catalog for the format.

Hole chart per part

In Export Hardware BOM, set Report to Hole chart per part and choose CSV or HTML. The chart lists, for every part a Hole Series drilled, each hole's entry point in that part's own component coordinates (X, Y, Z in mm) and its axis, the feature (diameter, thread, slot, Dowel H7), the tap drill, a counterbore or countersink, a nut pocket and the depth. A part used several times is charted once, because its holes belong to its definition. Holes made by other features are not included, and a series whose parts cannot be read is listed as a note to rebuild.

Assembly Cut / Intersect

Select one solid body as the tool and one or more target bodies. The source tool remains unchanged. Each unique native target definition receives correctly transformed snapshot geometry and one native Combine feature; repeated occurrences share that definition.

Directly linked targets use the same one-action source-file handoff as Hole Series. Hole Series & Fasteners snapshots the parent cutter in assembly-world coordinates, closes the clean parent, applies the correctly transformed cut inside each source, then restores and updates the parent. Create, Edit, Update All, and Delete preserve the source/coordinator relationship.

Edit, Update All, and Audit

Edit can change supported treatments, dimensions, operations, and the Assembly Cut cutter. Hole Series also offers the complete position-selection replacement described below. A distributed object's linked source-file set is fixed; delete and recreate the object when parts must be added or removed.

Replace hole centers during Edit

1. Open Edit Assembly Feature and select the managed Hole Series.
2. Leave Replace hole centers off to keep its saved positions, or turn it on to select a replacement set.
3. Select the complete desired set, including positions you want to retain. This replaces the set; it does not merely append new holes. Use the same supported point, circular-edge or cylindrical-face references as Create. Local connections can be moved or have positions added or removed this way.
4. For applicable point selections, use the direction reference and flip controls as needed. Review the saved and replacement counts and coordinates. This is selection feedback; the dialog does not build temporary cut solids. Geometry stays unchanged until OK.
5. Confirm the edit after checking the complete set. Linked edits validate their source relationships before any source changes are written.

Hardware checks before linked source changes

Linked Hole Series Create and rebuild check the planned head and nut fit and every placement's automatic or manual screw length and engagement before handing off to source-file edits. Invalid hardware stops before source changes or cloud saves. Hardware is checked again after the parent references update. A later failure is still a partial linked job with retained cloud checkpoints; these checks do not create an all-file rollback.

The linked Hole Series editor exposes hole size, fit, head/tail treatments and their supported dimensions. Size and head-treatment changes use Create's recess defaults; changing only the head retains explicit clearance and nut-pocket dimensions. An inch countersink is 82°; a size without a sourced flat head falls back from Countersink to Counterbore.

Its managed Fastener Stack is owned by the Hole Series and is read-only in the separate Edit selection. The parent Hole Series editor does not yet expose manual hardware length, requested engagement, washer/nut toggles, independent Follow options, hardware-dimension overrides or a create/remove hardware toggle. Those controls are available where supported in ordinary local Fastener Stack Edit. Stored custom values are preserved by rebuild; this does not make them editable in the linked parent UI.

Local rebuild is transactional: if replacement geometry fails, Hole Series & Fasteners attempts to restore the previous local specification and geometry. Linked-file work is journaled rather than falsely presented as one atomic cloud transaction. Every affected CAD file is preflighted before the first source-model or cloud write. If a later file fails, Hole Series & Fasteners does not erase or automatically compensate a source version already saved to Autodesk cloud. It stops, preserves all committed checkpoints, and reports the partial job for diagnosis instead of applying a saved source version twice.

A linked job that stops before it saves any file ends there: the message says No file was changed, Hole Series & Fasteners reopens the parent assembly and you can run the command again once the reported problem is fixed. When a job stopped after saving some files and cannot be resumed, Hole Series & Fasteners blocks further changes and Update All lists each file the job saved (with its version) and each file it did not. Check those files, then tick Release the lock and confirm: the job is archived as released by you. Releasing never resumes the job and never changes a file.

Update All processes distributed objects sequentially. Each successful distributed object creates one new version of every unique affected source and one new parent version; a later local rebuild stage can save one additional parent version. Update All does not run Get Latest or pull external source-file changes automatically: first make every affected parent reference current with Fusion's Get Latest or update-reference command.

Licensing and activation

The Autodesk Marketplace build checks the signed-in Autodesk account for an entitlement. If no Marketplace entitlement is present, the same background check can recognize a VanThanBK activation code or manual grant. The free trial lasts 3 days and begins only when you first use a protected Hole Series & Fasteners command while signed in and online. Merely starting Fusion or opening About Hole Series and Fasteners does not consume the trial. Open that command to see status, enter a code, or request a refresh. Network checks never run on Fusion's modeling thread.

A signed offline cache is scoped to this product, App ID, and Autodesk user. It is stored under the current user's VanThanBK application-data folder. The unlocked Autodesk review build performs no identity, cache, or licensing network access.

Connection recipes and selected size changes

In Hole Series, choose a Connection recipe, then select fresh centers and target bodies. Twelve supplied recipes cover metric fixtures, through bolts, a captive nut, a flush panel, UNC/UNF examples and a PEM mounting hole. Recipe dimensions remain editable design starting points, not load-rated joints.

Open Connection Library and Batch Change from the Hole Series panel menu. Choose Save connection recipe, select one managed Hole Series with at most one linked stack, and enter a unique name. Save/apply retains hole and hardware settings without storing model references. Import recipes and Export recipes exchange a validated JSON library.

For Batch change size, use Current size to show all sizes or one size used in the design. The Managed connections list identifies each connection by its ID, name, size, treatments and local or linked-file scope. Check individual rows or use Select matching to select the displayed records; Clear selection unchecks them. Changing the current-size filter or action clears the previous selection, so hidden records are never changed. Choose New size and review the selected, applicable and skipped counts with each skip reason. Changing the new size keeps the selection and refreshes the preview. Geometry changes only after you press OK.

Standard dimensions follow the size; custom dimensions and manual lengths remain explicit overrides. Incompatible overrides, independent hardware sizes and distributed connections are skipped with a reason. Linked stacks rebuild after their hole series. Linked-file changes continue to use Edit Assembly Feature.

A failed dependent update restores the previous connection. If restoration fails, the batch stops and keeps a snapshot in the design; choose Recover interrupted change. Other modeling commands block while recovery is pending. Save/recovery of the Fusion document controls persistence of unsaved work. Downstream user-created face references can still require repair after replacement geometry.

UNC/UNF hardware and supplier data

Fourteen UNC/UNF combinations cover #6, #8, #10, 1/4, 5/16, 3/8 and 1/2 inch. The inch family has Socket, Button and 82° Flat heads for every size, Hex heads from #10, hex and nylon-insert lock nuts, and flat washers. Tapped holes use the exact native Fusion thread designation and internal 2B class. Hardware is a lightweight supplier-reference envelope with no helical thread geometry.

Inch clearance presets are editable design allowances, not certified fit tables; preferred lengths do not guarantee supplier availability. Verify the purchased thread, dimensions, grade, finish and load requirements. Use Map supplier SKU with an HSF part number from Hardware BOM to add purchasing metadata. Import company catalogue validates before replacing your personal override file; Export company catalogue saves effective dimensions and mappings. Existing geometry changes only when explicitly rebuilt.

Tail insert > PEM-S-M4-1ZI creates a 5.41 mm mounting hole in the last local target. It checks minimum 1.00 mm sheet thickness and normal drilling direction. Verify +0.08/-0 mm hole tolerance, minimum 6.9 mm center-to-edge distance, HRB80/HB150 maximum sheet hardness and the supplier's installation process. It requires M4 with Clearance termination and Add fasteners off. Insert deformation, retention strength and insert BOM quantities are not modeled. Rivnut/heat-set installation data is not supplied without a verified supplier record.

See Connection library and supplier sources for detailed scope, provenance and JSON workflow. Manufacturer reference: PEM S-M4-1ZI.

For the metric head and nut envelopes, see Fastener reference dimensions.

Local data, privacy, and support

Object definitions are stored in the Fusion document as versioned attributes. Personal settings and optional company fastener overrides are stored under VanThanBK/HoleSeriesAndFasteners in the current user's application-data folder. Linked workflows save CAD versions through Autodesk Fusion cloud data. No CAD geometry is sent to VanThanBK or its licensing service.

On Windows, the folder is %APPDATA%\VanThanBK\HoleSeriesAndFasteners. Edit metric_fasteners.json there to apply company dimensions, standard labels and supplier mappings. Include only the keys you want to override. The file is read again on the next Create or Update, so unspecified values can still receive improvements from the bundled catalog.

Two optional keys shape the Hardware BOM. grades adds a grade to the designations of one kind of hardware, for example {"socket": "12.9", "hex": "8.8", "nut": "8", "washer": "200 HV"} (kinds: socket, hex, button, countersunk, flange, washer, nut, nut_nylon, nut_flange, pin). search_url is an https address with one {query} where the designation goes, so the links search your supplier's site instead of the web.

Privacy policy: vanthanbk.com/privacy
Product and purchase information: Hole Series & Fasteners
Offline guide: Hole Series & Fasteners Help
Support: vanthan92e1@gmail.com (English or Vietnamese).

Current limitations

• Create, Edit, Update and batch changes require a Hybrid parent. Document types are not converted automatically.
• A feature in a shared component definition appears in every occurrence of that definition.
• Direct linked source files and parts linked inside linked subassemblies are supported, up to 5 link levels. A nested part that is reached through more than one subassembly, or that is also linked directly in the parent, is refused. Linked subassemblies that are saved must be Hybrid designs, closed before the job, and use the latest version of every nested part.
• Derived, configured, read-only and stale source targets are unsupported. Make affected references current before a linked operation.
• Linked-file Edit keeps the affected source-file set fixed. Adding or removing a source requires Delete and Create. Hardware recipes and selected batch size changes are limited to local managed connections.
• Replace hole centers uses a complete replacement selection. Retained linked axes keep their original point and direction references even if a different reference at that same axis is selected. The dialog reports selection counts and coordinates without temporary cut-solid geometry.
• Parent-side editing of a linked connection does not expose the local Fastener Stack's full hardware controls, including manual length, requested engagement, washer/nut toggles and independent Follow options.
• Linked jobs save source files sequentially. Cloud versions already committed remain if a later stage fails; there is no all-file rollback. Review the retained checkpoint journal for a partial job.
• Run Hole Series & Fasteners mutation commands from only one Fusion process for the current Windows user at a time. Its recovery journal is shared per user; Audit Assembly is read-only.
• Hole Series and Assembly Cut require Capture Design History. Fastener Stack also supports Direct Modeling.
• Entity tokens can change after a rebuild. Hole Series & Fasteners stores occurrence/component context as well, but a deleted source reference is rejected instead of rebuilding at an unsafe cached world coordinate. Linked sources must match the captured file, version and geometry; references are not recovered by guessing from body names.
• Faces or edges referenced by downstream native Fusion features may need to be selected again after replacement geometry is generated. Edit and Update place replacement geometry near its previous timeline position.
• Slots are made in local components only. Their direction is kept in assembly coordinates; pick it again after rotating the slotted part.
• A mounting face reads round holes only. A size read from a diameter is a best match to the clearance, tap drill or nominal sizes; check it before OK.
• No sourced data: fine-pitch Button, Countersunk and flange nuts, inch flange hardware, #6 and #8 hex heads, dowel pins above 20 mm. These are refused instead of guessed.

Development roadmap

The next work focuses on editing connections across linked files. These items are planned or under development; they are not available-feature claims or release-date commitments.

• More hardware controls from the parent: expose manual length, requested engagement, washers, nut options and Follow settings for a linked connection's managed hardware, retaining the existing checks before source changes.
• Recipes and batch changes for linked connections: extend reusable hardware recipes and selected size changes to distributed connections while preserving source coordination and recovery information.
• Configured and derived parts: investigate configured and derived targets, including shared definitions and update order. (Parts in linked subassemblies are already supported; see Linked parts inside linked subassemblies.)